Solid Modeling Christmas Tree
In this project, I will show you how to create a Christmas tree surrounded by deer using SolidWorks.
I started by designing the deer. I created their heads and bodies by connecting points in sketches and turning those shapes into 3D models. By changing the dimensions and positions of different parts, I made deer in different poses, including standing and resting.
Next, I designed the main Christmas tree as one solid piece and added decorations, a star, and smaller trees. Finally, I arranged all the deer and trees together on a circular base to complete the design.
This tutorial will explain the tools, measurements, and steps needed to recreate the project, even if you are new to SolidWorks.
Downloads
Supplies
Required:
- Computer or Laptop – A computer capable of running SolidWorks.
- SolidWorks Software – Used to design all the 3D models and assemble them.
- Mouse – Recommended for drawing sketches, selecting tools, and rotating 3D models.
Optional (For 3D Printing):
- 3D Printer – To turn the finished digital model into a physical decoration.
- PLA Filament – The material used to print the model.
- 3D Slicing Software – Such as Cura or Prusa Slicer, to prepare the STL file for printing.
Set Up SolidWorks
Before creating the deer, we need to prepare the workspace.
- Open SolidWorks.
- Click File → New → Part → OK.
- Look at the bottom-right corner and change the measurement units to MMGS (millimeter, gram, second).
- Click File → Save As and name your file.
- On the left side of the screen, find the Feature Manager Design Tree. You should see Front Plane, Top Plane, Right Plane, and Origin.
- Select Front Plane → Sketch.
- Press Ctrl + 8 to look directly at the sketch plane.
For this tutorial, we will use the X-axis for the deer's body length, the Y-axis for its height, and the Z-axis for its width.
Helpful tip: When drawing a sketch, select a point to edit its position. You can use Smart Dimension or the point's coordinate fields to set measurements.
Sketch the Deer's Body
We will create the body by connecting several points with a smooth curve.
- Select Front Plane → Sketch.
- Click Sketch → Spline.
- Click six points from left to right to form the upper outline of the deer's body.
- Double-click to finish the spline.
- Select each spline point and adjust its X and Y coordinates using the following reference values.
- Select Sketch → Line.
- Draw a straight horizontal line from the last spline endpoint back to the first endpoint.
- Make sure the line and spline form one closed area.
- Exit Sketch.
You should now see the upper half of an oval-shaped body with a flat bottom edge.
Turn the Body Into a 3D Shape
- Select Features → Revolved Boss/Base.
- Under Axis of Revolution, select the horizontal line connecting the two spline endpoints.
- Enter 360° for the revolution angle.
- Check the yellow preview.
- Click the green checkmark.
The sketch should rotate around the horizontal line, creating a rounded, three-dimensional deer body.
If the feature fails, check that the spline does not cross the horizontal line and that there are no gaps in the sketch.
Create the Deer's Head
We will use the same point-connecting method to make the head.
- Select Front Plane → Sketch.
- Click Sketch → Spline.
- Draw another curve using six points.
- Double-click to finish the spline.
- Adjust the points using these reference coordinates:
- Select Line.
- Connect the final point to the first point with a horizontal line.
- Exit Sketch.
- Select Features → Revolved Boss/Base.
- Select the horizontal line as the axis.
- Enter 360°.
- Click the green checkmark.
The head should have a narrower front and a wider back.
It will be separate from the body for now. We will connect the two pieces by creating the neck.
Create the Neck
The neck connects the body and head using three circular cross-sections.
- Select Features → Reference Geometry → Plane.
- Select Top Plane as the reference.
- Enter an offset of 37mm toward positive Y. Use Reverse Direction if the plane appears below the origin.
- Click the green checkmark.
- Select the new plane → Sketch.
- Draw a circle with a 14mm diameter.
- Position its center at X = 8mm, Z = 0mm.
- Exit Sketch.
- Create two additional planes and circular sketches base on the graph
- After creating all three circles, select Features → Lofted Boss/Base.
- Under Profiles, select the three circle sketches from bottom to top.
- Check the preview. The neck should curve upward toward the head.
- Enable Merge result if available and applicable.
- Click the green checkmark.
The neck should overlap both the body and head.
If they remain separate solid bodies, check that the neck intersects both pieces. You can use Insert → Features → Combine → Add to join overlapping solid bodies within the same part.
Create the First Front Leg
We will use three circular cross-sections to create a leg.
- Select Top Plane → Sketch.
- Draw a circle with a diameter of 7mm.
- Position its center at X = 10mm, Z = 8mm.
- Exit Sketch.
Now create the second cross-section:
- Select Features → Reference Geometry → Plane.
- Select Top Plane and set the offset to 16mm upward.
- Click the green checkmark.
- Select the new plane → Sketch.
- Draw another 7mm diameter circle.
- Position its center at X = 7mm, Z = 8mm.
- Exit Sketch.
Create the third cross-section:
- Make another plane 35mm above Top Plane.
- Draw a circle with an 11mm diameter.
- Position its center at X = 12mm, Z = 8mm.
- Exit Sketch.
Now connect the circles:
- Select Features → Lofted Boss/Base.
- Select the circles in order, starting from the bottom.
- Check that the loft connects them smoothly.
- Enable Merge result so the leg connects to the body.
- Click the green checkmark.
You should now see one front leg extending from the body toward the ground.
Create the First Back Leg
Repeat the previous process, but use these measurements base on the graph
- Use the existing Top Plane and offset planes.
- Create the three new circular sketches.
- Select Features → Lofted Boss/Base.
- Connect the circles in order.
- Enable Merge result.
- Click the green checkmark.
The deer should now have one front leg and one back leg on the same side of its body.
Create the Other Two Legs
Instead of building two more legs from scratch, we can mirror the existing legs.
- Select Features → Mirror.
- Under Mirror Face/Plane, select Front Plane.
- Under Features to Mirror, select the two leg loft features from the Feature Manager tree.
- Check the preview.
- The mirrored legs should appear on the opposite side of the deer.
- Click the green checkmark.
The deer should now have four legs.
If the mirror fails, check that you selected the leg features rather than the complete deer body.
Create the Ears
- Click Features → Reference Geometry → Plane.
- Select Front Plane and offset it 5mm toward positive Z.
- Select the new plane → Sketch.
- Click Sketch → Line.
- Connect these three approximate points to make a triangular ear:
- (-22, 69)
- (-26, 84)
- (-12, 75)
- Connect the last point to the first point.
- Exit Sketch.
- Select Features → Extruded Boss/Base.
- Extrude 5 mm outward, away from the center of the head.
- Enable Merge result if the ear intersects the head.
- Click the green checkmark.
To create the opposite ear:
- Select Features → Mirror.
- Choose Front Plane as the mirror plane.
- Select the ear extrusion feature.
- Click the green checkmark.
You can use Features → Fillet with a small radius to soften the ears' sharp edges.
Add the Eyes and Final Details
- Create a plane parallel to Front Plane, approximately 7mm toward the visible side of the head.
- Select this plane → Sketch.
- Draw a small circle approximately 2.5mm in diameter near X = -23mm, Y = 68mm.
- Exit Sketch.
- Select Features → Extruded Boss/Base.
- Extrude the circle approximately 2mm toward the outside of the head.
- Enable Merge result if the feature overlaps the head.
- Click the green checkmark.
- Mirror the eye feature across Front Plane to create the second eye.
You can also add a small nose using the same method.
After completing the details, rotate the deer to check the body, head, neck, and four legs.
Save the file using Ctrl + S in STL form.
Create Different Deer Poses
Now that the standing deer is complete, we can change its dimensions to create a resting deer.
- Select File → Save As.
- Choose Save as copy and open.
- Name the new file.
- Find the body revolve feature in the Feature Manager tree.
- Expand the feature and right-click its sketch.
- Select Edit Sketch.
- Change the body spline points to the value of first graph
- Keep the closing line connected to the first and last spline points.
- Exit Sketch.
Next, edit the head sketch and use the value of second graph
- Edit the neck's reference planes, changing their heights from 37,51, and 64mm to 18,30, and 37 mm.
- Keep the neck circle diameters unchanged.
- Edit the front and back leg lofts.
- Change the middle leg plane height from 16mm to 6mm, and the upper leg plane from 35mm to 14mm.
- Move the front foot's center to approximately X = 22mm and the back foot's center to X = 43mm.
- Keep the feet close to the bottom of the body.
- Move the ear and eye sketches downward by approximately 27 mm.
- Press Ctrl + B to rebuild the model.
The body should now sit lower, and the legs should appear tucked beneath it.
If a feature displays an error after the changes, right-click that feature, select Edit Feature, and check its references and selected sketches.
Save the resting deer as STL.
You can create additional poses by saving more copies and changing the head height, body proportions, and leg positions.
Create the Main Christmas Tree
- Select File → New → Part.
- Set the units to MMGS.
- Select Front Plane → Sketch.
- Click Sketch → Centerline.
- Draw a vertical centerline through the origin.
- Select Sketch → Line.
- Create the tree's side profile by connecting the following approximate points in order.
- Draw one final straight line along the centerline, connecting Point 21 to Point 1.
- Make sure the entire outline is closed.
- Exit Sketch.
- Select Features → Revolved Boss/Base.
- Select the vertical centerline as the revolution axis.
- Enter 360°.
- Click the green checkmark.
You should now have a complete solid Christmas tree with several layers of pointed branches.
Save it as STL
Create the Smaller Christmas Trees
We can reuse the main tree instead of drawing every smaller tree again.
- Open Tree STL, before adding its decorations.
- Select File → Save As → Save as copy and open.
- Name the copy Small_Tree.SLDPRT.
- Select Insert → Features → Scale.
- Under Scale About, choose Origin.
- Enable Uniform Scaling.
- Enter a Scale Factor of 0.32.
- Click the green checkmark.
The smaller tree should now be approximately 56 mm tall.
Save it as STL.
You can create more copies with scale factors of 0.26 and 0.36 to make trees of different sizes.
Create the Spiral Ribbon
The ribbon will wrap around the main Christmas tree.
First, create its path.
- Select Features → Reference Geometry → Plane.
- Create a plane parallel to Top Plane,15mm above the origin.
- Select this plane → Sketch.
- Select Sketch → Circle.
- Draw a circle centered on the tree's central axis.
- Use Smart Dimension to set its diameter to 80mm.
- Exit Sketch.
- Select Insert → Curve → Helix/Spiral.
- Under Defined By, choose Height and Revolution.
- Set Height to 115mm.
- Set Revolutions to 1.8.
- Enable Taper Helix.
- Enter a Taper Angle of approximately 14°.
- Leave Taper outward unchecked so the spiral narrows as it rises.
- Check the preview and reverse the helix direction if it extends downward.
- Click the green checkmark.
You should now see a spiral curve extending upward around the tree.
Next, turn the curve into a solid ribbon.
- Select Features → Reference Geometry → Plane.
- Select the spiral curve and its starting point.
- Create a plane perpendicular to the curve at that point.
- Select the new plane → Sketch.
- Draw a small rectangle approximately 10mm wide and 4mm thick.
- Position the rectangle so the spiral passes through its center.
- Exit Sketch.
- Select Features → Swept Boss/Base.
- Choose the rectangle sketch as the Profile.
- Select the spiral as the Path.
- Check the preview and click the green checkmark.
The ribbon should follow the spiral around the tree.
If the ribbon is too far from the tree or disappears inside it, edit the starting circle diameter or taper angle. Adjust these values until the ribbon sits around the outside of the branches.
Create the Door
- Select Features → Reference Geometry → Plane.
- Create a plane parallel to Front Plane, offset 19 mm toward positive Z.
- Select this plane → Sketch.
- Choose Sketch → Line.
- Draw a horizontal bottom line from X = -10mm to X = 10mm at Y = 16mm.
- Draw a vertical line upward from each end to Y = 38mm.
- Select Sketch →3Point Arc.
- Connect the two upper endpoints with an arch that rises to approximately Y = 48 mm.
- Make sure the doorway outline is completely closed.
- Exit Sketch.
- Select Features → Extruded Boss/Base.
- Set the extrusion depth to 15mm toward the front of the tree.
- Enable Merge result.
- Click the green checkmark.
You should now have a raised, arched doorway on the front of the tree.
To add the inner door details:
- Select the flat front face of the doorway → Sketch.
- Draw a smaller doorway outline inside the original one.
- Exit Sketch.
- Select Features → Extruded Cut.
- Enter a depth of 1 mm.
- Click the green checkmark.
Repeat with smaller outlines to create multiple decorative arches.
Add Christmas Ornaments
We will create raised circular decorations on the tree.
- Create a plane parallel to Front Plane, approximately 22mm toward positive Z.
- Select this plane → Sketch.
- Draw a circle with a diameter of 8mm near X = -18mm, Y = 24mm.
- Exit Sketch.
- Select Features → Extruded Boss/Base.
- Extrude approximately 12mm toward the front of the tree.
- Enable Merge result and click the green checkmark.
- Select the circular front face of the decoration.
- Choose Insert → Features → Dome.
- Set the dome distance to approximately 3mm.
- Click the green checkmark.
You should now have a rounded ornament.
Repeat the process in several locations. For higher ornaments, create their sketches on planes closer to the center of the tree, since the tree becomes narrower toward the top.
If an ornament does not intersect the tree, move its starting plane inward before extruding it.
Create the Star
- Click Sketch → Line.
- Draw a five-pointed star by connecting ten points, alternating between the outer tips and inner corners.
- Make the star approximately 34mm wide and position its center near Y = 185mm.
- Connect the last point to the first to form a closed outline.
- Exit Sketch.
- Select Features →Create the Star
- Extruded Boss/Base.
- Set End Condition to Mid Plane.
- Enter a thickness of 6mm.
- Click the green checkmark.
Now connect the star to the tree.
- Select Front Plane → Sketch.
- Draw a narrow rectangle centered on the vertical axis.
- Make the rectangle 4mm wide, extending from Y = 168mm to Y = 184mm.
- Exit Sketch.
- Select Extruded Boss/Base → Mid Plane.
- Enter a depth of 6 mm.
- Make sure the rectangular support intersects both the tree and the star.
- Enable Merge result.
- Click the green checkmark.
Your main Christmas tree is now complete.
Save the file.
Create the Circular Base
- Select File → New → Part.
- Select Top Plane → Sketch.
- Click Sketch → Circle.
- Click the origin to set the circle's center.
- Draw the circle.
- Select Smart Dimension.
- Set the diameter to 200mm.
- Exit Sketch.
- Select Features → Extruded Boss/Base.
- Enter a depth of 6mm, making sure it extrudes upward.
- Click the green checkmark.
- Select Features → Fillet.
- Click the outer top circular edge of the base.
- Enter a radius of 2mm.
- Click the green checkmark.
- Save the file as STL
You should now have a flat circular base with rounded edges.
Start the Final Assembly
- Select File → New → Assembly.
- Click Insert Components.
- Browse for Christmas Base STL
- Insert it at the assembly origin.
- Click Insert Components again.
- Add Main Tree STL
- Insert Standing Deer STL
- Insert one or more copies of Resting Deer STL
- Insert several copies of Small Tree STL
All the components should now appear in the assembly.
Position the Main Tree
- Select Assembly → Move Component.
- Select the main Christmas tree.
- Use the To XYZ Position option to place its origin near X = 0, Y = 6, Z = 0.
- Click Apply.
- Close the Move Component tool.
- Select Assembly → Mate.
- Select the flat bottom face of the tree.
- Select the flat top face of the circular base.
- Choose Coincident.
- Click the green checkmark.
The main tree should now stand upright in the center of the base.
Arrange the Deer
- Select Assembly → Move Component.
- Select the standing deer.
- Move it toward one side of the base.
- Use Rotate Component to change the direction it faces.
- Position the deer's feet on the base.
- Use Mate to align the deer's Top Plane with the top face of the base, so the bottom of its feet sits at the correct height.
- Repeat the process for the resting deer.
For a layout similar to the reference image, place the standing deer near the left side and arrange the resting deer toward the front and right side.
Check the placement from multiple angles. The deer should not float above the base or extend too far outside its edge.
Add the Smaller Christmas Trees
- Select one of the smaller trees.
- Click Move Component.
- Move it beside the main tree.
- Align its bottom face with the top surface of the circular base.
- Use Mate → Coincident.
- Repeat for the other small trees.
- Rotate and reposition them until the arrangement looks balanced.
Place smaller trees between the deer and around the main tree to create more detail and depth.
Some small trees can be positioned close to the main tree, similar to the reference design.
Check the Assembly
- Press the middle mouse button and drag to rotate the assembly.
- Inspect the model from the front, back, and sides.
- Check that the deer and smaller trees are positioned correctly.
- Make sure the decorations and star are visible.
- Check for unwanted gaps and intersections.
- Adjust the component positions if necessary.
- Select File → Save As STL
- Name the file Christmas Tree Final
The digital assembly is now complete.
Prepare the Model for 3D Printing
An assembly contains separate components. If you want to produce one connected 3D print, you need to check the geometry carefully.
- Open the final assembly.
- Make sure all components are correctly positioned.
- Ensure the feet of the deer and the bottoms of the smaller trees intersect the base slightly where they need to connect.
- Check that the star and other decorations connect to the main tree.
- Select File → Save As.
- Change the file type to SOLIDWORKS Part (*.SLDPRT).
- Use the assembly-to-part saving options to include all required components.
- Save the new part and open it.
- Expand the Solid Bodies folder on the left.
- If multiple overlapping solid bodies remain, select Insert → Features → Combine.
- Choose Add.
- Select the bodies that need to be joined.
- Click the green checkmark.
If the Combine feature fails, check whether the selected bodies actually overlap. Bodies that are separated by a gap cannot be joined using Combine → Add.
Continue checking the remaining solid bodies until the model has the intended connected geometry.
Export the Model
- Open the completed part or assembly.
- Click Options.
- Select Binary format.
- Choose Fine resolution.
- Check that the units are millimeters.
- If you are exporting directly from an assembly, enable Save all components of an assembly in a single file.
- Click OK.
- Click Save.
Open the exported STL file in your slicing software.
Check the dimensions and print preview before starting a print. Pay particular attention to the thin legs, ears, branches, and star, which may need additional support or adjustments.
Final Result
The final design combines a large Christmas tree, smaller trees, different deer poses, a star, decorations, and a circular base. The extra part is the holding structure automatically done by the 3D print app; you can select not to print the holding.
I started by creating the deer using points connected into sketches and turning those shapes into 3D models. By changing the dimensions and positions of their features, I created different deer poses.
I then created the main Christmas tree as one solid shape, added the decorations, and assembled everything into the final Christmas display.
The completed model can be saved as a SolidWorks assembly or exported as an STL file for 3D printing.